Post-process Stress Results (solver independent)

  1. From the Contour panel, select the data type that should be used to calculate the contours (for example: Displacement (v), Stress (t), 1D stress, Energy (s), etc.) from the Result type drop-down menu.
    The available result types change depending on the result file that is loaded.
    Tip: Click the expansion button to open the Choose From List dialog, where you can filter result types for faster selection.
  2. Select a data component type from the second drop-down menu in the result type section.
    The list of available components is based on the selected result type. For example:
    Result type Component options
    Displacement (v) Mag, X, Y, or Z.
    Stress (t) vonMises, Signed vonMises, P1(major), P2(mid), P3(minor), Pressure, MaxShear, Intensity, In-plane P1(major), In-plane P2(minor), XX, YY, ZZ, XY, YZ, or ZX.
    1D stress Multiple options are listed for various elements such as: CELAS, CROD, CBAR, CBEAM, etc
    Energy (s) No component selection is necessary.
  3. If corner data is available, choose if a nodal or element value should be used by checking/unchecking the Use corner data option (see the element stress examples below).
      Averaging: None Averaging: Simple/Advanced
    Use corner data off One value per element: centroid value taken from result file.

    		 One nodal value for all corresponding elements: averaged from each centroid value.
    Use corner data on IP value mapped to nearest node, OR, Nodal result from result file (whichever of the two is available): values are not averaged at node.

    		 One nodal value for all corresponding elements: averaged using corresponding corner data values (either IP or nodal result from result file).

  4. For Selection, pick one or more entities from the model.
  5. Select the coordinate system that will be used to calculate the results from the Resolved in drop-down menu.
    Note: If User System is selected, use the System input collector to select a system by ID.
  6. Use the Averaging method drop-down menu to select the averaging type of the element contribution at the shared element node (see the element stress examples below).
    Only one element contoured: Averaging at nodes with values from that element.


    Figure 1.
    Values that are averaged at nodes have contributions from all of the attached elements.


    Figure 2.
  7. Activate the Variation (%) check box and enter a percentage for the variation range.
  8. Activate the relevant check boxes for Display options, Legend threshold, and Result display control.
  9. Click Apply to display the contour plot.
    For Abaqus .odb files
    The following results are available from *.odb files:
    • Centroid values
    • Integration point values: S-Stress component or S-Stress component IP (Integration Points), depending on the result type.
    • Nodal results: S-Stress component or S-Stress component IP (Integration Points), depending on the result type.
      Averaging: None Averaging: Simple/Advanced
    Use corner data off One value per element: centroid value taken from result file. One nodal value for all corresponding elements: averaged from each centroid value.
    Use corner data on

    IP value mapped to nearest node

    (S-Stress Components IP)

    OR

    Nodal result from result file

    (S-Stress Component)

    In both cases, values are not averaged at node.

    One nodal value for all corresponding elements averaged using corresponding corner data values:

    IP value (S-Stress Component IP)

    OR

    Nodal result (S-Stress Component) from the result file.
    For *.op2 and *.h3d results
    SHELL elements Solver output default - values are available at the centroid:
    • Use corner data option is not available.
    • Averaging can be done on centroidal results (None, Simple, or Advanced).
    When CORNER, BILIN, or CUBIC have been called in the solver - nodal results will be available in the result file for each element:
    • Use Corner Data option is available.
    • Corner data = nodal results are taken directly from the result file.
    • Averaging can be done in Altair HyperView on the values taken from the result file.